PCB Gold Fingers: Edge Connector Design Guide

Gold fingers are the gold-plated contact pads along the edge of a PCB that slide into a card-edge connector. You see them on RAM modules, graphics cards, PCI/PCIe cards, and industrial backplane systems. The hard gold plating (typically 30-50 microinches) withstands thousands of insertion cycles without significant wear. This guide covers gold finger design rules, plating specifications, bevelling requirements, and ordering tips for Indian PCB projects.

Table of Contents

• Gold Finger Basics
• Gold Plating Specifications
• Design Rules
• Edge Bevelling
• Common Connector Types
• Layout Tips in KiCad
• Ordering from Manufacturers
• Frequently Asked Questions

Gold Finger Basics

Gold fingers are different from ENIG surface finish. ENIG uses a thin layer of gold (0.05-0.1µm) over nickel for soldering purposes. Gold fingers use hard gold plating (0.75-1.25µm, or 30-50 microinches) over a thicker nickel barrier (2.5-5µm) specifically for wear resistance in plug-in connectors.

Gold Plating Specifications

For edge connector applications, specify hard gold plating to your fabricator:

• Gold thickness: 30µ” (0.75µm) for standard applications (200-500 insertion cycles), 50µ” (1.25µm) for high-reliability or frequent-insertion applications
• Gold purity: 99.7% minimum, hardened with 0.1-0.3% cobalt
• Nickel underplate: 100-200µ” (2.5-5µm) of electroless nickel as a diffusion barrier
• Hardness: 130-200 Knoop (vs 60-85 Knoop for ENIG soft gold)

The cost of hard gold plating is typically ₹500-2,000 per panel depending on the total finger area. It is a separate electroplating step that requires masking the rest of the board.

Design Rules

Critical design points:

• No solder mask on gold finger area — the entire connector contact zone must be bare gold
• No silkscreen in the finger area
• No copper traces running between fingers on outer layers
• Inner layer copper should be pulled back 1mm from the board edge in the finger area to prevent copper exposure during bevelling

Edge Bevelling

Edge bevelling (also called chamfering) creates an angled cut at the board edge where the gold fingers are located. This angle guides the board into the connector slot and prevents damage to the gold plating during insertion.

• Standard bevel angle: 20-30 degrees
• Bevel depth: 0.2-0.5mm (removes approximately 1/3 of the board thickness at the edge)
• Direction: Bevelled on both top and bottom surfaces (symmetrical)
• Cost: Minimal — usually included when gold fingers are ordered

Specify bevelling in your fabrication drawing with the angle, depth, and which edge requires bevelling. Most fabricators do this automatically when gold fingers are ordered, but confirm to avoid issues.

Common Connector Types

For custom designs, card-edge connectors are available in 2.54mm pitch (standard) and 1.27mm pitch (high-density) from manufacturers like Amphenol, TE Connectivity, and Samtec. Match your PCB finger design to the specific connector datasheet.

Layout Tips in KiCad

1. Create a custom footprint for the gold finger contact area with pads placed at the board edge
2. Set the pad type to “SMD” with no solder mask (or add them as pad openings on the mask layer)
3. Place the footprint so pad edges align with the Edge.Cuts line
4. Add a note in the fab layer indicating “Hard gold plating 30µ” on this edge”
5. In the board outline, ensure the gold finger edge is perfectly straight — no routing tabs or castellations on this edge
6. Run DRC to verify no mask or silk encroaches on the finger area

Ordering from Manufacturers

When ordering PCBs with gold fingers:

• Select “Gold Fingers” as an option (not just ENIG surface finish)
• Specify the gold thickness (30µ” or 50µ”)
• Specify bevelling requirements (angle and which edge)
• Board thickness must be specified precisely — card-edge connectors are sensitive to thickness
• JLCPCB, PCBWay, and most Indian fabricators offer gold fingers. Expect 3-5 extra working days for the additional plating step

Frequently Asked Questions

Can I use ENIG instead of hard gold for edge connectors?

ENIG will work for very low insertion count applications (under 50 cycles). For development boards that are only plugged in a few times, ENIG may be acceptable. For any product that will be plugged and unplugged regularly, hard gold is essential — ENIG will wear through within 20-30 insertions, causing intermittent contact failures.

How much does gold finger plating cost?

At JLCPCB, gold fingers add approximately $10-20 to a standard 5-board prototype order. At Indian manufacturers, expect ₹500-2,000 per panel depending on the finger area size. The cost is driven by the gold plating area and thickness — more fingers or thicker gold costs more.

Can I have gold fingers and ENIG on the same board?

Yes, this is common. The rest of the board pads use ENIG (or another finish) for soldering, while the edge connector area receives hard gold. The manufacturer masks the gold finger area during the standard surface finish process, then applies hard gold separately.

What board thickness should I use?

Match the connector specification. Standard card-edge connectors accept 1.57mm (62 mil) or 1.6mm boards. Some connectors are designed for 2.0mm or 2.4mm boards. Always check the connector datasheet for the accepted board thickness range and tolerance.

Browse prototyping boards, connectors, and ESD protection supplies at Zbotic PCB & Prototyping — fast shipping across India.